generic Haas 4 axis vmc mm post help

[chris28]

Hi all

I am using generic Haas 4 axis vmc mm post on my 3 axis haas vf3 mill. How can i modify my post so it not out put A0.

Please help

[cobra95kev]

There I think should be a switch in there somewhere. I will look and try and find it.

 

 

Kevin C.

[cobra95kev]

In this section in your post try setting the rotary axis to 0 or off.

 

 

# --------------------------------------------------------------------------

# Rotary Axis Settings

# --------------------------------------------------------------------------

vmc : 1 #SET_BY_MD 0 = Horizontal Machine, 1 = Vertical Mill

rot_on_x : 1 #SET_BY_MD Default Rotary Axis Orientation

#0 = Off, 1 = About X, 2 = About Y, 3 = About Z

rot_ccw_pos : 0 #SET_BY_MD Axis signed dir, 0 = CW positive, 1 = CCW positive

index : 0 #SET_BY_MD Use index positioning, 0 = Full Rotary, 1 = Index only

[Guest]

In your post set this to 0

 

code:

---

rot_on_x    : 0     #Default Rotary Axis Orientation, See ques. 164. 

#0 = Off, 1 = About X, 2 = About Y, 3 = About Z

---

[Paul Decelles]

No.

 

The Generic Haas 4X Mill.pst reads the Machine Definition and automatically sets the rotary axis switches based upon the rotary axis defined in the active axis combination. To remove the 'A' output, open the Machine Definition in the MD Manager, click on the Axis Combination icon on the top bar, uncheck the rotary axis in the default axis combination and save the MD.

[Guest]

Well at least I didn't suggest the MPMaster.

 

[chris28]

Thank you for all yours replied. Why didn't think of MPMaster. Stupid me.

[Paul Decelles]

Which also reads the Machine Definition...

[cadcam]

Right on Paul.

[cobra95kev]

Does anyone have any idea how to eliminate the space between the parenthesis and the man readable comments using this post?

 

Here is what I am getting. The haas control doesn't like it

 

( T#1 1.0" endmill )

 

here is what I am after:

 

(T#1 1.0" endmill)

 

I have tried messing with the comments section in the post and have had no luck.

 

Thanks a bunch

Kevin C.

[Post dept]

If you're outputting your code with spaces, as you must be to get the output you are, you have a couple of options. There are a couple of ways to deal with this, the preferred method is just add no_spc$ after the first bracket and before the last bracket.

 

Chris

[cobra95kev]

Thanks Chris,

That sure did the trick.

 

Kevin C.

[Josh T™]

I know this is an old thread but I'm having a similar issue....

 

quote:

---

The Generic Haas 4X Mill.pst reads the Machine Definition and automatically sets the rotary axis switches based upon the rotary axis defined in the active axis combination. To remove the 'A' output, open the Machine Definition in the MD Manager, click on the Axis Combination icon on the top bar, uncheck the rotary axis in the default axis combination and save the MD.

---

I did this and set the rot_on_x to "0" but it still outputs A axis statements.

 

 

Anyone have a clue? Using X3

[Tony35]

josh t

dumb question but did you reload the MD and to a regen of the toolpaths with the new MD?

[Josh T™]

Of Course I did....

 

Just "Joshin" with you!

 

I've tried everything. I'm thinking about starting on the MPMaster but I'd really like to get this working. I spent some time getting the output right.

[Tony35]

how do you have the axis combo set all checked but the A axis?

 

maybe try setting it like this just with x y axis and table not the whole group without A axis

 

[Josh T™]

This is how I have the axes set up:

 

 

The only thing unchecked is the A axis. Am I doing something wrong?

[Tony35]

where is it putting the A moves in the program?

[Josh T™]

code:

---

 %

O12( WEAR-PLATE )

(PROGRAM SOLUTIONS)

(MACHINE CNC: HAAS VF-SERIES 3AXIS)

(DATE: 25-09-09)

(PROGRAM GENNERATED IN MASTERCAM vers_no$ 12.)

(PROGRAMER - JOSHUA TURNER)

()

(TOOLS)

( T2 | 3/8 DRILLMILL | H2 )

( T1 | 5/8 DRILL | H1 )

( T3 | 13/32 DRILL | H3 )

( T4 | LTR. U DRILL | H4 )

( T5 | 1/2 FLAT ENDMILL | H5 | XY STOCK TO LEAVE - .01 | Z STOCK TO LEAVE - 0. )

( T6 | 3/8 FLAT ENDMILL | H6 )

( T7 | 3/8 REAMER | H7 )

G28

G20

G0 G17 G40 G49 G80 G90

T2 M6

G0 G90 G54 X0. Y2.875 A0. S2000 M3

G43 H2 Z1. T1

G98 G81 Z-.15 R.1 F5.

X-2.035 Y1.504

X-3.5 Y0.

X-2.035 Y-1.559

X-3.375 Y-2.875

X0. Y0.

X1.024 Y-1.559

X3.375 Y-2.875

X3.5 Y0.

X2.276 Y1.504

G80

M5

G91 G28 Z0.

A0.

M01

---

[Tony35]

ok its been awhile since i have played with a haas but i had 2 posts setup 1 for index and one for just 3 axis to get the A out remove this from the post at tool change, null tool change, start of non zero tool #

 

pcan1, pbld, n$, *sgcode, *sgabsinc, pwcs, pfxout, pfyout, pfcout,<<<<<<<<

 

take pfcout out of the line

[Jayson Kramer]

Check and see what line 164 says "Y" or "N"

 

161. Enable Home Position button? y

162. Enable Reference Point button? y

163. Enable Misc. Values button? y

 

"164. Enable Rotary Axis button? y"

 

165. Enable Tool Plane button? y

166. Enable Construction Plane button? y

167. Enable Tool Display button? y

168. Check tplane during automatic work origin creation? y

[Josh T™]

Just got around to replying. I removed the pfcout and the protretinc and it works great. I still don't understand why the MD doesn't work?

[Mr. Wizzard]

Similar question. It seems that I can never get settings in the MD, CD to over-ride the post. X3 or X4.....

 

Using the Haas 4-axis post, MD,CD from X4 on a Haas TM-2 with 4th axis.

 

I was able to get the A-axis working on X3 MU1, but no luck, so far, in X4. I'm trying to get G93 Inverse Time Feedrates output and it's not working. I get the Inverse Feedrates on every line, but a G94 where there should be a G93.

 

Also, does not post "A" rotation on first line when only posting one op. Only G54 X.... Y....

 

I don't get why I can't get the MD to set things right when the post specifically says it's over-ridden by the MD/CD? I only got things to work in X3 by changing the MD/CD AND the post

 

Any help would be greatly appreciated!

[Bryan Johnson]

Modifying the machine definition should work. The problem there is when you write a lot of programs for the same machine, some with and some without using the rotary.

Another way to handle this is to setup the post file so that it scans the program, and if no rotary moves are found, it does not output and rotary moves. That way you can use the same files for both.

On the FTP site, look for "Mill_Haas-VF" post files.

[BrianP.]

quote:

---

Does anyone have any idea how to eliminate the space between the parenthesis and the man readable comments using this post?

 

Here is what I am getting. The haas control doesn't like it

---

Just curious what the Haas didn't like about it. I actually like the space and use it all the time. Have a VF-2 and VF-6 and never a problem with the Haas controller or any other for that matter.